home login search menu close-circle arrow-dropdown-up arrow-dropdown arrow-down arrow-up close hide show info jump-link play tip external fullscreen share view arrow-cta arrow-button button-dropdown button-download facebook youtube twitter tumblr pinterest instagram googleplus linkedin email blog lock pencil alert download check comments image-carousel-arrow-right show-thick image-carousel-arrow-left user-profile file-upload-drag return cta-go-arrow-circle circle circle-o circle-o-thin square square-o square-o-thin triangle triangle-o triangle-o-thin square-rounded square-rounded-o square-rounded-o-thin cta-go-arrow alert-exclamation close-thick hide-thick education-students globe-international cloud sign-in sign-out target-audience class-materials filter description key-learning pdf-file ppt-file zip-file plus-thick three-circle-triangle transcript-outline

Worldwide Sites

You have been detected as being from . Where applicable, you can see country-specific product information, offers, and pricing.

Change country/language X

You can’t download the Fusion 360 trial on this device, but you can email yourself a link to download later on your Mac or PC.

Thanks for your interest in Fusion 360, an email is on its way!

Looking to access a Fusion 360 project on your mobile device?

Get the Fusion 360 mobile app on:

Keyboard ALT + g to toggle grid overlay

CAM

To get you started with CAM in Fusion 360, these videos will provide an introduction and get you oriented with the CAM environment.

Overview

Begin with this course overview covering the Fusion 360 CAM Environment, Toolbar and CAM Browser.

  • Fusion 360 CAM course overview

  • What is Fusion 360 CAM

  • Fusion 360 CAM interface

  • The CAM browser

How to's

File locations, Folders and Stock Setup options. Drilling holes in the model.

  • Toolpath simulation display

  • Stock setup 

  • Select drilling locations

Hands-on Exercises

Now you’re ready to put your skills into practice.  Try these hands-on exercises to get started.

  • Import a CAD file

  • Define stock and work coordinate system

  • Spot drill

  • Drill through

  • Countersink and tool edit

  • Verify toolpath with simulate

Import a CAD File

x/x  

 

Goals:

  1. Launch Fusion 360.
  2. Create a new Project.
  3. Upload an existing Part file. 
  4. Open the Part file in Fusion 360.

Instructions:

  1. Open the exercise file “Lesson 1 procedure 1.stp”.
    You can download the part file here: http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_1/16intCAM_exercise_1.zip
  2. Launch Fusion 360.
  3. Click on the 'Show Data Panel' button.

4. Click on the 'New Project' button.

5. Name the project 'Mill 2D Lessons'.

6. Double click on the 'Mill 2D Lessons' project to open it in Fusion 360.

7. From the 'Project' screen click on the 'Upload' icon and 'Drag and Drop' or 'Select' the file to upload it. 

8. Click on the 'Upload' button.

9. Once the file is uploaded click on the close button. 

10. Right click on the Lesson 1 file and click 'Open' or double click on the part.

11. The part is now open in Fusion 360.

Self-Check

1. Click and drag the Grip component. Is the Shaft sliding in and out of the
Base? Is the Connector rotating as well as translating with the components?

  • If so, good job!
  • If not, make sure that there are six joints showing in the Browser, totaling to 3 Revolute joints, 1 Cylindrical joint, 1 Ball joint, and 1 Rigid joint. Also make sure that the Base is grounded.

Define Stock and WCS

x/x  

 

Goals:

  1. Create a new Setup.
  2. Set the Work Coordinates of the part.
  3. Define the Stock settings.
  4. Define the Program Name or Number.

Instructions:

  1. Open the exercise file “Lesson 1 procedure 2.f3d”.
    You can download the part file here:
    http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_2/16intCAM_exercise_2.zip
  2. Open the Setup parameter screen by clicking on the 'Setup' icon. 

3. In the Work Coordinate System (WCS) change the Orientation to ‘Select Z
axis/plane & X axis’.

4. Click on the ‘Face’ button and select the top face of the model.  

5. Click on the X axis ‘Button’ and then select the edge of the model.

6. Change the Origin to 'Model origin'.
7. Select the 'Stock' tab.

8. Change the Stock 'Mode’ to 'Relative size' box.

9. Change the ‘Stock Offset Mode’ to ‘No additional stock’.

10. Set ‘Round Up to Nearest’ to 0 (zero) in.

11. The ‘Dimensions’ of the ‘Stock’ are 4in for X, 3in for Y and 0.25in for Z.

12. Select the Post Process tab.

13. Leave the ‘Program Name/Number’ set to 1001.

14. Change the ‘Operations’ name to ‘Lesson 1 Setup’.

Self-Check

1. Stock: What are the Dimensions of the part? Check the ‘Stock’ parameter screen
in Setup. Do the dimensions match the following? 

Width (X) 4in, Depth (Y) 3in, Height (Z) 0.25in

  • If so, good job!
  • If not, double check that your settings in ‘Stock’ are correct.

Self-Check

 Stock: Where is the Work Offset of the part? Are the XYZ arrows on the top corner of the model, as shown in the image here?

  • If so, good job!
  • If not, double check that your settings in ‘Stock’ are correct.

Spot Drill

x/x  

 

Goals:

  1. Select the proper Spot Drill from the Tool Library.
  2. Select the Geometry to be Spot Drilled.
  3. Create the Drilling Toolpath.

Instructions:

  1. Open the exercise file “Lesson 1 Procedure 3.f3d”.
    You can download the part file here:
    http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_3/16intCAM_exercise_3.zip
  2. Click on the Drilling icon in the CAM Toolbar.
  3. Click on the Tool Select button in the Drill Parameter Screen.

4. In the Tool Library change the Workpiece Material setting to Steel.

5. Ensure the Operation is set to Hole.

6. Change the Tool Type to Spot Drill

7. Select the #70-1/2" spot drill from the samples.

8. Change the Surface Speed to 300.

9. Change the Feed per Revolution to 0.002.

10. Select the Geometry tab. 

11. Select the 'Select Same Diameter' check box. 

12. Finally, select the edge of the counter sink hole. 

13. Select the Heights Tab.
14. Change the Top Height to Hole top.
15. Change the Bottom Height to To Chamfer Diameter
16. Change the Chamfer Diameter to 0.3

17. Select the Cycle Tab.

18. Set the Cycle Type to Counterboring - dwell and rapid out.

19. Set the Dwelling Period to 0.25.

Self-Check

1. Spot Drill: Does the screen look similar to the image below?

  • If so, good job!
  • If not, double check that the settings in the Geometry tab.

Drill Through

x/x  

 

Goals:

  1. Determine the diameter of the 4 holes.
  2. Drill four 9/32” through holes.

Instructions:

  1. Open the exercise file “Lesson 1 procedure 4a.f3d”.
    You can download the part file here:
    http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_4a/16intCAM_exercise_4a.zip
  2. Click on the Drill icon in the CAM Toolbar. 
  3. Use Fusion zoom to check the diameter of one of the through holes.

4. Once the diameter has been determined, click on the tool select button.

5. Then set the parameters as shown here, and select the 9/32" drill from the Tool
Library.

6. Select the Geometry Tab and enable the ‘Select Same Diameter’ and ‘Optimize Order’ options.

7. Then select the face of the through hole on the part.  

8. Switch to the ‘Heights Tab’ and change the ‘Top Height’ to ‘Stock Top’ or  ‘Model Top’.

9. Set the ‘Bottom Height’ to ‘Hole Bottom’. 

10. Turn on ‘Drill Tip Through Bottom’ and set the ‘Break-Through Depth’ to 0.025.

11. Switch to the ‘Cycle Tab’ and change the ‘Cycle Type’ to ‘Drilling - rapid out’.

11. The part is now open in Fusion 360.

Self-Check

1. Drill Through: Does the drill go through the part?
Use Simulate and change the view to front to make sure the drill goes through the part.

  • If so, good job!
  • If not, double check that Top Height is set to Hole top in the Heights parameter screen.

Countersink and Tool Edit

x/x  

 

Goals:

  1. Use the Inspect function to determine the size of countersink needed.
  2. Edit an existing tool and copy it to the library.
  3. Use the Derived Toolpath function to create countersink toolpaths.

Instructions:

  1. Open the exercise file “Lesson 1 procedure 4b.f3d”.
    You can download the part file here:
    http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_4b/16intCAM_exercise_4b.zip
  2. Click on the Inspect icon in the CAM Toolbar.
  3. Click on the edge of the large diameter of the countersink.

4. Once the diameter has been determined click on the Tool Library icon.

5. Then copy the existing ½” countersink to the Lesson 1 Documents Library.

6. Edit the ½” countersink tool to ¾”, change the tip angle to 82 degrees and the tip diameter to 0.050”.

 

7. Right-click on the Spot Drill operation in the browser. Under "Create Derived Operation", go to "Drilling," and select "Drill".

8. Select the Tool select button in Tool parameter screen.  

9. Turn off the Tool Type and Diameter filters and select the newly created ¾” counter sink.

10. Adjust the Spindle Speed to 550 and Plunge Feedrate to 10.

11. Switch to the Heights Tab.

12. In the Top Height section, select Hole top in the “From” drop-down menu. 

13. Rename the toolpath to “CounterSink”.  

Self-Check

1. Counter Sink: Does the countersink
drill to the correct depth?

Use Simulate and change the view to Front to make sure the countersink drills to the correct depth.

  • If so, good job!
  • If not, double check that Top Height is set to Hole top in the Heights parameter screen.

Verify toolpath with simulate

x/x  

 

Goals:

  1. Simulate all 3 toolpaths.
  2. Check for collisions.
  3. Verify part conformance visually.

Instructions:

  1. Open the exercise file “Lesson 1 procedure 5.f3d”.
    You can download the part file here:
    http://app.solidprofessor.com/weblms/html5/16intCAM_exercise_5/16intCAM_exercise_5.zip
  2. Click on the "Lesson 1 Setup" to select all toolpaths. 
  3. Click on the "Simulate" icon in the CAM toolbar to launch the simulation.

4. Run the simulation with "Stop on Collision" enabled.

5. When the simulation completes, examine the resulting solid for part conformance.

 

  1. Collisions: Did the simulation stop during playback? 
  2. Conformance: Do the simulated holes match the model?
  • If so, Good job!
  • If not, double check the setup and each operation.

8. Switch to the ‘Heights Tab’ and change the ‘Top Height’ to ‘Stock Top’ or  ‘Model Top’.

9. Set the ‘Bottom Height’ to ‘Hole Bottom’. 

10. Turn on ‘Drill Tip Through Bottom’ and set the ‘Break-Through Depth’ to 0.025.

11. Switch to the ‘Cycle Tab’ and change the ‘Cycle Type’ to ‘Drilling - rapid out’.

11. The part is now open in Fusion 360.

Self-Check

1. Drill Through: Does the drill go through the part?
Use Simulate and change the view to front to make sure the drill goes through the part.

  • If so, good job!
  • If not, double check that Top Height is set to Hole top in the Heights parameter screen.